Create/Update Drawing - Automatic

Management + BIM > Workshop > Drawing

Use this function to

Auto-create workshop and detail drawings and
Update workshop, detail, mounting and customer drawings after changing the model drawing.

In contrast to the Create/Update - Manual function the settings for drawing derivation (e.g. for Drawing sheets, View groups, Views etc.) will not be specified in the dialogue window here, but will be loaded from the corresponding pre-settings files when you create the workshop/detail drawings. Therefore, the Drawing derivation dialogue will not be displayed here, which speeds up the drawing creation process.

Mounting drawings and customer drawings cannot be created with this function, but only updated (if there are any drawings). However, the updating will only work if the drawings have the status In progress. In this context, please also read the information given in the chapters Customer Drawings, Mounting Drawings and Change Released Drawings.

When you call the function it will be checked

for which parts of the model drawing no workshop or detail drawing exists yet,
which drawings (including mounting and customer drawings) are no longer up to date, and
whether parts for which drawings existed have been deleted in the model drawing.

The result will be shown in a selection mask. Here, all articles with the links

Drawing not up to date,
Mounting drw. not up to date,
Customer drw. not up to date and
Deleted

will be listed.

Select the parts for which a drawing needs be created (or updated), and click OK. The selected parts will be highlighted in the model drawing and the following message appears:

When you click on Yes, the drawings for the highlighted parts will be updated or deleted.

Please note that drawings belonging to deleted parts will only be removed after project clean-up.
See also Delete Drawing.

Then, all parts with the "Without drawing" link (i.e. all parts for which no production drawing exists yet) will be listed.

Now, select the parts for which you want to create production drawings and confirm with OK. The selected parts will be highlighted in the drawing and the following message appears:

Click Yes to create the drawings for the selected parts. Inputs in the Drawing derivation window are not required here, since the settings for drawing derivation will be loaded from the appropriate presetting files here.

The workshop drawing will be created immediately as a Sheet a new model drawing. Sheet views can be opened in the Views tab of the ICN.

By default, the following template files are supplied with HiCAD(in the SYS directory):

File	Settings for
BIM_WSD_Default_Assembly.DAT	Assemblies	ISD default setting
BIM_WSD_Default_IndividualPart.DAT	Individual parts	ISD default setting
BIM_WSD_Default_Bolted_Assembly.DAT	Bolted assemblies (Site)	ISD default setting
BIM_WSD_Default_Welded_Assembly.DAT	Welded assemblies (Workshop)	ISD default setting

In the supplied settings files, the drawing parameters will be specified via configuration, i.e. the settings in the Configuration Editor at Automatic drawing derivation > Production drawing > Usage-dependent will be used. This means:

For general assemblies to which no usage has been assigned the settings at ...Usage-dependent > DEFAULT will be used.
For assemblies to which a usage has been assigned, the settings for the corresponding usage at ...Usage-dependent will be used, e.g. for beam (girder) assemblies the settings at ... >Usage-dependent > ASSEMBLY_BEAM.
For individual parts of the type Flat steels, Hollow profiles, I-beams or steel pipes the corresponding settings at ...Usage-dependent will be used,e.g. for I-beams the settings at ...Usage-dependent > DEFAULT(I_PROFILE). For other beams and profiles, the settings at ... >Usage-dependent > DEFAULT(PROFILE) will be used.

For individual parts to which no part type has been assigned, the settings at ... >Usage-dependent > DEFAULT will be used.

For bolted and welded assemblies ("Site" and "Workshop" assemblies) the settings at ... >Usage-dependent > DEFAULT used.

Example:

If an external production document, e.g. a PDF file, has been opened in HELiOS, a drawing that is linked to it cannot be updated in HiCAD.

Please note:

When you create or update production drawings, the settings in the Configuration Editor at PDM > Management + BIM > External production drawings will be considered.

If the setting Upon Checkup and Release has been chosen for the Create ... files for production drawings parameters beneath External drawing data, the corresponding DXF, DWG or PDF files will be created for the production drawings. Please note that a Postprocessor needs to be specified for PDF files.

Derived drawings which have been automatically generated with the Management + BIM functions are locked against manual modifications. When you try to change any parts in the drawing, the following message will be displayed: Automatically detailed parts cannot be processed in automatically created external production drawings.
The parts of the automatically created drawings are (unilaterally) referenced in the direction of the original drawing and marked in the ICN with the symbol. The referencing is unilateral, i.e. in case of changes to the model, the workshop drawing can automatically be updated.

Ensure that the required HiCAD catalogues (Fasteners etc.) are also available in HELiOS. If this is not the case, you need to transfer them, via the Catalogue Editor, to HELiOS.(for further information please see the Online Help of the Catalogue Editor).
The settings in the Configuration Editor at PDM > Management + BIM will be considered for drawing derivations.

When adding view groups in Sheets with already existing views of a derived drawing, you have nor the option to deactivate the rearranging of the existing views. This setting can be speicified in the Configuration Editor at ... > Automatic drawing derivation > Production drawing > Rearranging existing views when adding view groups - Do not rearrange. The default setting is Query.

For external PDM-managed drawings you can now specify whether missing sectional views are to be created in case of an updating of derived drawings. In the Configuration Editor, select ... > PDM > Steel Engineering Drawing Management and set the parameter AutoSync sectional view when updating PDM-managed drawings as required. The default setting is Adjust.

It is also possible to switch off the automatic rearranging of views. In the Configuration Editor. Select ... > PDM > Management+BIM and set the parameter Rearrange views when updating PDM-managed drawings as required. The default setting is Rearrange.

Do not use this function for an automatic updating of production documents! Instead, use the functions in the Production function group for this.

If an automatically generated article master is not used in a super-ordinate article master, and a part with no links exists, the product structure of the part will be deleted before a general clean-up takes place.

If released customer drawings with old parts exist for the current model drawing, the following message will be displayed:

This will, for instance, be the case if, after a release of customer drawings, changes are applied to parts in the 3-D model that belong to one of these customer drawings.

After clicking OK, a list of the old parts will be displayed.

To be able to update these customer drawings, you first need to call the Revision index function and choose the corresponding customer drawing to remove the Release again. Then, choose the Drawing function to update the customer drawing. The status of the drawing will then be reset to In progress. With the functions in the Customer... pull-down menu you can then request an approval and release the drawing again.

Use the Locked old drawings function to check whether locked customer drawings with old parts exist.

If an external production document, e.g. a PDF file, has been opened in HELiOS, a drawing that is linked to it cannot be updated in HiCAD. In such as case HiCAD will issue the message shown below and list the documents in another window:

In this situation you have the option to end the editing by choosing (Extras > Show workspace ) and clicking on the symbol in the HELiOS workspace dialogue window. When you then perform an update, the opened external document, too, will be updated in the background. When you open this document again, all changes will then be visible.

Creating your own settings files

Besides the option to use the predefined settings files supplied with HiCAD, you can also create, depending on the respective usage/part type, your own settings files.

To create or modify such files, select Drawing > Itemisation/Detailing > Derive . Specify the desired settings in the dialogue. To Save the settings in a settings file, or to Load an existing file, use the buttons beneath Settings file.

The area in the red frame is controlled by the corresponding .DAT file, the area in the green frame by the settings in the Configuration Editor.

The presetting files must be given the following names:

BIM_WSD_UsageText.DAT or

BIM_WSD_UsageKey.DAT

with UsageText standing for the designation in the tables of the Factory Standards catalogue Usage, and UsageKey standing for the CONFIGKEY.

Catalogue	Table	UsageKey = CONFIGKEY	UsageText = Designation
General	Column	COLUMN	Columns
General	Girder	BEAM	Girder
Metal Engineering - Elements	Contact profile	MC_STRIP	Contact profile
	Cover bar	MC_COVERBAR	Cover bar
	Seal	MC_GASKET	Seal
	Inserted profile	MC_INSERTIONBAR	Inserted profile
	Isolator	MC_ISOLATOR	Isolator
	Support profile	MC_PROFILE	Support profile
	Connector	MC_CONNECTOR	Connector
Metal Engineering - Groups	Fixing bracket	BEFESTIGUNGSKONSOLE	Fixing bracket
	Inserts	MC_LOGIKALOBJECT	Insert
	Top or base point	MC_BRACKET	Facade base point Facade top point
	Mullion	MC_MULLION	Mullion
	Mullion connection	PFOSTENSTOSS	Mullion connection
	Transom	MC_BAR	Transom
Steel Engineering - Assemblies	Stabilizing pipe	STABILIZING_PIPE	Stabilizing pipe
	Cross-bracing	CROSS_BRACING	Cross-bracing
	Steel frame	FRAME	Frame
	Welded beam/profile	WELDED_I_SECTION	Welded I-beam
		WELDED_BOX_SECTION	Welded box profile
		WELDED_CROSS_SECTION	Welded cross-profile
		WELDED_SEMICROSS_SECTION	Welded cross-profile, half
	Column assembly	ASSEMBLY_COLUMN	Column assembly
	Girder (beam) assembly	ASSEMBLY_BEAM	Girder (beam) assembly
Steel Engineering	Plate types	FILLER-PLATE	Filler plate
		BASE-PLATE	Base plate
		TOP-PLATE	Top plate
		STIFFENER	Stiffener
		REINFORCEMENT-PLATE	Reinforcement plate
	Railing	SKIRTING	Skirting board
		SKIRTINGPROFILE	Skirting board profile
		WEBMEMBER	Rod
		FILLING	Infill
		RAILING	Railing
		RAILINGSEGMENT	Railing segment
		STRINGER	Boom
		HANDRAIL	Handrail
		RAILINGPROFILE	Handrail profile
		KNEERAIL	Kneerail
		POST	Post
		POSTPROFILE	Post profile
		GLASSPANE	Glass

Alternatively, you can also use the part type: BIM_WSD_Teileart.DAT. This file must be created, for instance, if you

want to define special settings for standard beams and profiles,
have defined part types, e.g. own profiles for profile installation tasks, or
renamed part types that had been predefined by the ISD.

For example, if you require particular settings for I-beams, you need to create a BIM_WSD_I - Profile.DAT file.

Part type	Catalogue	Part type	Catalogue
A1 Girder	Factory standards > Factory beams > Frankstahl	Glass panes	Factory standards
A3 Steel bar	Factory standards > Factory beams > Frankstahl	Hollow profiles	Factory standards > Factory beams > Frankstahl > A4 Shaped tubes, Hollow profiles, Profiles
General	Factory standards > Usage > Civil Engineering	Wood	Semi-finished products
B1 Commercial tubes, seamless	Factory standards > Factory beams > Frankstahl	IN-HOUSE_PROFILES	Factory standards > Factory beams
B2 Commercial tubes, welded	Factory standards > Factory beams > Frankstahl	Cold-rolled sections	Semi-finished products
B4 Mechanical stress-resistant steel pipes	Factory standards > Factory beams > Frankstahl	Crane rails	Semi-finished products > Beams+Profiles
B5 Precision steel pipes	Factory standards > Factory beams > Frankstahl	L - beams	Semi-finished products > Beams+Profiles
B6 Hydraulic components	Factory standards > Factory beams > Frankstahl	Profiles	Semi-finished products Factory standards > Factory beams > Frankstahl > A4 Shaped tubes, Hollow profiles, Profiles
Reinforced steel	Semi-finished products > Beams+Profiles	Round steels	Semi-finished products > Beams+Profiles
Plates	Semi-finished products	Hexagonal steels	Semi-finished products > Beams+Profiles
C-beams	Semi-finished products > Cold-rolled sections	Steel pipes	Semi-finished products > Beams+Profiles
C1 Pipes and Profiles	Factory standards > Factory beams > Frankstahl	T - beams	Semi-finished products > Beams+Profiles
C3 Stainless steel bars	Factory standards > Factory beams > Frankstahl	U - beams	Semi-finished products > Beams+Profiles Semi-finished products > Cold-rolled sections
Flat steel	Semi-finished products > Beams+Profiles	Square steel	Semi-finished products > Beams+Profiles
FLUTZ profile	Factory standards > Factory beams	Voest profiles	Factory standards > Factory beams
Formed tubes	Factory standards > Factory beams > Frankstahl > A4 Shaped tubes, Hollow profiles, Profiles	Z - beams	Semi-finished products > Beams+Profiles
Gratings	Semi-finished products

During automatic drawing creation HiCAD will check for each usage / part type whether pre-settings already exist, namely, in the following order:

If a settings file BIM_WSD_UsageText.DAT exists for a usage, this file will be used, and Step 1 will be repeated for the next usage. If such a file does not exist, the search will be continued with Step 2.
If no settings file BIM_WSD_UsageText.DAT exists,HiCAD will search for a BIM_WSD_UsageKey.DAT file. If such a file exists it will be used, and this step will be repeated for the next usage. If such a file does not exist, the search will be continued with Step 3.
If neither the file BIM_WSD_UsageText.DAT nor the file BIM_WSD_UsageKey.DAT exists, the default files will be used for assemblies. For individual parts, HiCAD will search for files with the name BIM_WSD_PartType.DAT. If such files exist, these will be used for the corresponding part types. For all other part types, the settings from the file BIM_WSD_Default_IndividualPart.DAT will be used.

Example:

Let us assume that, besides the default settings flies, the following files exist:

BIM_WSD_Column assembly.DAT and
BIM_WSD_I - beams.DAT.

In this case, the settings from the file BIM_WSD_Column assembly.DAT will be used for all assemblies with the usage Column assembly; for all other assemblies, the settings from the default files will be used, i.e. the settings from the file BIM_WSD_Default_Assembly.DAT for general assemblies, and the settings from the files BIM_WSD_Default_Bolted_Assembly.DAT or BIM_WSD_Default_Welded_Assembly.DAT, respectively, for bolted assemblies or welded assemblies, respectively.

For individual I-beams (not part of an assembly), the settings from the file BIM_WSD_I - beams.DAT will be used; for all other individual parts, the settings from the file BIM_WSD_Default_IndividualPart.DAT will be used.

Tip:
Please also note the functions at Drawing > Itemisation/Detailing > Attr... that enable you to apply various adjustments for drawing derivation, the assigning of article and document attributes etc.
This applies in particular to the Templates, Attribute assignment function that allows you to define the templates for attribute assignment of the Document and Drawing Management in Civil Engineering (Management+BIM) and for DSTV-NC export.

Overview of Functions (ManBIM) • Requirements for a Smooth Operation (ManBIM) • Pre-planning of the Construction Process (ManBIM) • Examples (ManBIM) • Drawing Derivation