Project: HiCAD Dach/Wand/Fassade

Example: Variable Installation Elements - The i_nr Variable

Installation elements can also be defined variably. For this purpose, the i_nr variable can be used. A number of corners n will be assigned to this variable. This allows an installing of this element on sketch areas with 3 to up to n corners.

In addition, the variables of the 4th, 5th and nth corner point must contain a query for the number of corners of the sketch area, namely, as follows:

If you want the installation to be possible on rectangular sketch areas, you need to additionally use the variants i_l and i_h!

An example:

Let us assume that you want to create a pentagonal sheet with flanges as an installation element. This sheet is to be adjusted to - and subsequently installed on - triangular and rectangular areas.

The basic procedure is quite similar to that for the example with the triangular sheet. However, the variable i_nr will be used here.

• Step 1 and 2: Create and parameterize the installation element
  
• Step 3: Define a Fitting CS
• Step 4: Save installation element to catalogue

Step 1 and 2: Create and parameterize the installation element

• Create a new drawing file and switch to the standard axonometry.

• Choose Sketch > New to create a new sketch.

• Choose Sketch > Draw > Line to draw two lines as shown below - one parallel to the Y-axis, the other one parallel to the X-axis. You will need these lines as an auxiliary geometry for parameterization, i.e. they virtually symbolize the coordinate system for the corner points of the pentagonal shape that you want to draw.
• To prevent that these auxiliary lines will be considered for the derivation of the sheet, define them as auxiliary geometry. To do this, choose Sketch > Tools > Sort GE > Auxiliary geometry and select the two lines. They will then be displayed as dashed lines.
• Choose Sketch > Draw > Line and draw a rectangle as shown below.

• Now, parameterize the pentagon via its corner points. Choose Sketch > HCM > Smart dimensioning and specify the distance constraints of the 3 corners to the vertical auxiliary line (HCM scaling = Scale complete sketch). Choose i_x0 and i_x1 to i_x4 as variables.
• Then, specify the distance constraints to the horizontal auxiliary line (variables i_y0 to i_y4).
• To ensure that the reference to the axes, i.e. to the two lines of the auxiliary geometries, will not be lost, these lines must be fixed. To do this, choose Sketch > HCM > Fix... and select the two lines of the auxiliary geometry.

• Since the installation element is to be used variably (.i.e. also suitable for triangular and square sketch areas), the parameter i_nr must be defined and applied to the 4th and 5th corner point, i.e. (i_x3,i_y3) and (i_x4,i_y4).

For this to happen, the constraints for the corner points must be changed in the HCM log (double click) in the following way:

Since the variable i_nr has not been defined yet, it will be queried. In this example, select the value 5.

• As the 1st corner point of the installation element is later to lie exactly in the corresponding corner of the sketch area, the variables i_x0 and i_y0 will be set to the value 0. To do this, open the Part variables docking window, change the value of i_x0 and i_y0 to 0, and confirm with OK.

• Now, derive the sheet from the sketch: Choose Sheet Metal > New > FromSkt , select the sketch, enter the sheet thickness and close the dialogue window with OK.

• To ensure that the sheet has the correct position for the later installing, move the sheet to the absolute zero point.

• Now attach the flanges. To do this, choose Sheet Metal > Attach Flange .

• The sheet thickness must be variable. To achieve a variable sheet thickness, change the corresponding Feature log entry and choose thickness as variable.

• The length of the flange must also be variable. To achieve a variable length, change the corresponding Feature log entries and choose Length as variable.

Step 3: Define a Fitting CS

The Fitting CS determines the insertion direction of a part in space. It consists of 3 special points:

• the origin,
• a point on the X-axis
• a point in the (X-/Y-) half plane

If a 3-D part to which a Fitting CS has been assigned is loaded into a new model drawing, the points of the Fitting CS will be placed into the World CS. In this way the insertion direction in space will be determined.

The definition of a Fitting CS is of particular importance if the installation element is an assembly. If this assembly is saved to the Element installation catalogue while no Fitting CS is assigned to it, the Part CS will be used as Fitting CS when the part is inserted. However, this may lead to unwanted results during the installing process.

Please note:

Not all assemblies have automatically a Feature log. For instance, this applies to assemblies that have been created with the Form assembly function, or via New > Assembly. If you assign a Fitting CS to these assemblies, no corresponding Feature log entry will be generated. To achieve this, you must assign a so-called body creation feature to the assembly. To do this, right-click on the Feature window of the assembly and select the corresponding function in the context menu. After this, the definition of the Fitting CS will be entered as a Feature here, too.

Continuation of the example:

As already mentioned, the sheet in this example is to be inserted in such a way that the first corner (i_x0, i_y0) lies in the bottom left corner of the selected sketch area. Therefore, a Fitting CS must be defined for the Sheet Metal main part.

Choose Drawing > Others > World CS > Define Fitting CS and proceed as follows:

(1) New origin of coordinate system is the bottom left corner of the pentagonal sheet (i_xo,i_yo), i.e. Absolute 0 0 0.

(2) Point on X-axis: R (Relative) 200 0 0

(3) Point on y-axis: R (Relative) 0 200 0

The Fitting CS will be entered into the Feature log.

The installation element has been completed and can now be saved to the catalogue.

To be able to directly create a preview image for the catalogue, switch to a non-shaded view beforehand.

Step 4: Save installation element to catalogue

To save an installation element to the catalogue, choose Drawing > Save/Reference > Part.. and use the settings shown below. Please make sure that the Sheet Metal main part is active!

• Choose the folder to which the part is to be saved as .KRA file. Preset has been the Element installation folder. To create a new folder, click the Make new folder button.
• Close the window with OK, go to Installation planning - Parts + Processings > Element installation > Installation elements, and select the table to which you want to assign the part.

In this example the folder Installation elements and the table Example have been selected. In the The "Element Installation" Catalogue chapter is is explained how tables for element installation must be composed.

• The ICON field has been initialized with the part name. Since you do not use a shaded view in this example, a preview image in the EMF format. When the following dialogue window appears...

... click Yes. This creates a preview image of the data record Pentagonal sheet from sketch, namely, in the sub-folder image of the folder selected for the .KRA file, i.e. for instance, Kataloge\Werksnormen\Elementverlegung\image

• The new installation element can now be installed on triangular, rectangular and pentagonal sketch areas, e.g. like this:

.

Please note:

• If you want the installation to be possible on rectangular grids, you need to additionally use the variants i_l and i_h (as you would do with rectangular installation elements).
• If the installation element is installed on a grid with more than 5 corners, only the first 5 corners of the installation area will be considered, e.g. like this:

Customer-specific Installation Elements • Catalogue Editor