Create/Update Drawing - Automatic (ManBIM)

Management + BIM > Drawing > AutoCreate/Update

Use this function to automatically create and update drawings. In contrast to the Create/Update Drawing - Manual function, the settings for drawing derivation (i.e. for drawing sheets, views, view groups etc.) will not be queried in the dialogue, but loaded from the corresponding settings files. This means that the Drawing derivation window will not be displayed here. In this way, drawing creation can be speeded up.

When you call the function, HiCAD will check

• which production drawings/mounting drawings are no longer up to date,
• whether parts in the model drawing were deleted for which a workshop/detail drawing existed, and
• for which parts in the model drawing no production drawing exists yet.

The result of the search will be shown in the Combined search mask of the HELiOS Desktop. Here, all parts of the model drawing with the links

• Mounting drawing not up to date
• Drawing not up to date and
• Deleted

will be shown.

Select the parts for which a drawing is to be created (or updated), and click OK. The selected parts will be highlighted in the model drawing and the following message appears:

When you select OK, the drawings for the highlighted parts will be updated or deleted.

Then, all parts with the "Without drawing" link (i.e. all parts for which no production drawing exists yet) will be listed. Non-existent mounting drawings will not be considered here.

Now, select the parts for which you want to create production drawings and confirm with OK. The selected parts will be highlighted in the drawing and the following message appears:

Click Yes to create the drawings for the selected parts. Inputs in the Drawing derivation window are not required here, since the settings for drawing derivation will be loaded from the appropriate presetting files here.

The workshop drawing will be created immediately as a Sheet view - either in the original model drawing or in a new drawing. Sheet views of the current model drawing can be opened in the Views tab of the ICN.

By default, the following template files are supplied with HiCAD(in the SYS directory):

File	Settings for
BIM_WSD_Default_Assembly.DAT	Assemblies	ISD default setting
BIM_WSD_Default_IndividualPart.DAT	Individual parts	ISD default setting
BIM_WSD_Default_Bolted_Assembly.DAT	Bolted assemblies (Site)	ISD default setting
BIM_WSD_Default_Welded_Assembly.DAT	Welded assemblies (Workshop)	ISD default setting

In the supplied settings files, the drawing parameters will be specified via configuration, i.e. the settings in the Configuration Editor at Automatic drawing derivation > Production drawing > Usage-dependent will be used. This means:

• For general assemblies to which no usage has been assigned the settings at ...Usage-dependent > DEFAULT will be used.
• For assemblies to which a usage has been assigned, the settings for the corresponding usage at ...Usage-dependent will be used, e.g. for beam (girder) assemblies the settings at ... >Usage-dependent > ASSEMBLY_BEAM.
• For individual parts of the type Flat steels, Hollow profiles, I-beams or steel pipes the corresponding settings at ...Usage-dependent will be used,e.g. for I-beams the settings at ...Usage-dependent > DEFAULT(I_PROFILE). For other beams and profiles, the settings at ... >Usage-dependent > DEFAULT(PROFILE) will be used.

• For individual parts to which no part type has been assigned, the settings at ... >Usage-dependent > DEFAULT will be used.

• For bolted and welded assemblies ("Site" and "Workshop" assemblies) the settings at ... >Usage-dependent > DEFAULT used.

Example:

Please note:

• This function only updates existing mounting drawings, but creates no new mounting drawings. If you want to create new mounting drawings, use the Mounting drawing function.
• When you create or update production drawings, the settings in the Configuration Editor at PDM > Management + BIM > External production drawings will be considered.

If the setting In case of checkup and release has been chosen for the Create ... files for production drawings parameters beneath External drawing data, the corresponding DXF, DWG or PDF files will be created for the production drawings. Please note that a Postprocessor needs to be specified for PDF files.

Creating your own settings files

Besides the option to use the predefined settings files supplied with HiCAD, you can also create, depending on the respective usage/part type, your own settings files. To create or modify such files, select Drawing > Itemisation/Detailing > Derive . Specify the desired settings in the dialogue. To Save the settings in a settings file, or to Load an existing file, use the buttons beneath Settings file.

The files must be given the following names:

• BIM_WSD_UsageText.DAT or

• BIM_WSD_UsageKey.DAT

with UsageText standing for the designation in the tables of the Factory Standards catalogue Usage, and UsageKey standing for the CONFIGKEY.

Alternatively, you can also use part types: BIM_WSD_PartType.DAT

For example, if you require particular settings for I-beams, you need to create a BIM_WSD_I - Profile.DAT file.

During automatic drawing creation HiCAD will check for each usage / part type whether pre-settings already exist, namely, in the following order:

1. If a settings file BIM_WSD_UsageText.DAT exists for a usage, this file will be used, and Step 1 will be repeated for the next usage. If such a file does not exist, the search will be continued with Step 2.
2. If no settings file BIM_WSD_UsageText.DAT exists,HiCAD will search for a BIM_WSD_UsageKey.DAT file. If such a file exists it will be used, and this step will be repeated for the next usage. If such a file does not exist, the search will be continued with Step 3.
3. If neither the file BIM_WSD_UsageText.DAT nor the file BIM_WSD_UsageKey.DAT exists, the default files will be used for assemblies. For individual parts, HiCAD will search for files with the name BIM_WSD_PartType.DAT. If such files exist, these will be used for the corresponding part types. For all other part types, the settings from the file BIM_WSD_Default_IndividualPart.DAT will be used.

Example:

Let us assume that, besides the default settings flies, the following files exist:

• BIM_WSD_Column assembly.DAT and
• BIM_WSD_I - beams.DAT.

In this case, the settings from the file BIM_WSD_Column assembly.DAT will be used for all assemblies with the usage Column assembly; for all other assemblies, the settings from the default files will be used, i.e. the settings from the file BIM_WSD_Default_Assembly.DAT for general assemblies, and the settings from the files BIM_WSD_Default_Bolted_Assembly.DAT or BIM_WSD_Default_Welded_Assembly.DAT, respectively, for bolted assemblies or welded assemblies, respectively.

For individual I-beams (not part of an assembly), the settings from the file BIM_WSD_I - beams.DAT will be used; for all other individual parts, the settings from the file BIM_WSD_Default_IndividualPart.DAT will be used.

Please note:

• Derived drawings which have been automatically generated with the Management + BIM functions are locked against manual modifications. When you try to change any parts in the drawing, the following message will be displayed: Automatically detailed parts cannot be processed in automatically created external production drawings.
• The parts of the automatically created drawings are (unilaterally) referenced in the direction of the original drawing and marked in the ICN with a symbol. The referencing is unilateral, i.e. in case of changes to the model, the workshop drawing can automatically be updated. If you want a bilateral referencing, change the setting in the Configuration Editor accordingly.

• Ensure that the required HiCAD catalogues (Fasteners etc.) are also available in HELiOS. If this is not the case, you need to transfer them, via the Catalogue Editor, to HELiOS.(for further information please see the Online Help of the Catalogue Editor).
• The settings in the Configuration Editor at PDM > Management + BIM will be considered for drawing derivations.

• When adding view groups in Sheets with already existing views of a derived drawing, you have nor the option to deactivate the rearranging of the existing views. This setting can be speicified in the Configuration Editor at ... > Automatic drawing derivation > Production drawing > Rearranging existing views when adding view groups - Do not rearrange. The default setting is Query.

• For external PDM-managed drawings you can now specify whether missing sectional views are to be created in case of an updating of derived drawings. In the Configuration Editor, select ... > PDM > Steel Engineering Drawing Management and set the parameter AutoSync sectional view when updating PDM-managed drawings as required. The default setting is Adjust.

It is also possible to switch off the automatic rearranging of views. In the Configuration Editor. Select ... > PDM > Management+BIM and set the parameter Rearrange views when updating PDM-managed drawings as required. The default setting is Rearrange.

• Do not use this function for an automatic updating of production documents! Instead, use the functions in the Production function group for this.

• If an automatically generated article master is not used in a super-ordinate article master, and a part with no links exists, the product structure of the part will be deleted before a general clean-up takes place.

 Related Topics

Derive Drawings (ManBIM) • Basic Procedures (ManBIM)