Neues Blech entlang Skizze (3D-Blech)

Sheet Metal > New > New sheet along sketch (Main part)

Sheet Metal > New > AlongSkt > Sub-part

Use the New sheet along sketch function to create a sheet from a drawn sketch, taking parameters such as bend radius, sheet thickness and sheet depth into account. Depending on the selected function, the sheet will be created as a main part or a sub-part. To create a main part, you first need to create a main assembly with a sub-assembly. After activating the assembly and calling the function, the base sheet will become a sub-part of the assembly.

1. Sketch

2. Sheet parameters

3. Bend zones

4. Fitting parameters

5. General

6. Apply or discard value inputs

Example

Sketch

Proceed as follows:

1. Draw a sketch in 3-D.

2. Select one of the two New sheet along sketch functions and identify the sketch.

After identification of the sketch, a preview of the new sheet will be displayed. If you want to identify a different sketch, click the icon in the Sketch area and identify the desired sketch.

To modify the sketch click the Process sketch icon. The Sketch tab and the Process sketch dialogue will then be displayed. Change the sketch and confirm with Apply sketch. The Sheet along sketch dialogue will then be displayed again.

3. Activate the Delete sketch after creation if you want to remove the sketch from the drawing and the ICN after the creation of the base sheet.

Sheet parameters

4. Enter the Sheet thickness, the Bend radius and the Allowance method for the blank.

If you activate the Use semi-finished product , a semi-finished product will be chosen from the Catalogue Editor, and no value input for sheet thickness will be required; instead, the Sheet thickness, the Material and the Article number will be taken from the Catalogue Editor. If you also want to take the bend radius from the Catalogue Editor, activate the  From semi-finished product checkbox beside the input field for the bend radius. In the Bend zones area the bend radius can even be changed if the  From semi-finished product checkbox has been activated.

To preserve the blank (development) of the modelled Sheet Metal part, HiCAD offers various developments according to different, common allowance methods that consider material-dependent length changes of workpieces during bending processes. Each allowance method is represented by a corresponding system file. These files have been prepared appropriately; in practice, however, users may want to store their own allowance methods in this way. Activate the  From semi-finished product checkbox beside the input field for the allowance method if you want to take the file from the Catalogue Editor.

Semi-finished products can also be activated/deactivated or changed subsequently. To do this, double-click the Sheet along sketch feature. The dialogue window for sheet creation will be displayed, where you can activate or deactivate the checkboxes for semi-finished products, or select a different semi-finished product by clicking the icon. Confirm with OK to apply the changes.

Bend zones

If you want to change the radius or the allowance method for a bend zone, expand the Bend zone area by clicking on the icon.

In the displayed table you can assign a value for the Bend radius and the Allowance method to each bend zone. Right-click to equalize the values in a column.

5. First select Value instead of Default setting for the bend zone and then enter a value.

Fitting parameters

6. Specify in the Offset direction field to which side the sheet thickness is to be applied.

The input will be immediately visualized in a preview.

7. Then, enter the sheet width and the fitting direction (-Z, +Z or Both sides) of the sheet width.

General

8. Activate the Referenced checkbox if you want the part to be saved as a referenced part (see HiCAD 3-D).

Frequently used parts should be saved as referenced parts. The part will then be additionally stored as an individual part at the end of the function process, and will not exist as a fixed part in the drawing. When applying changes to the individual part, you can update the part in the drawing afterwards.

Remove the checkmark from the Feature checkbox to deactivate the features during creation of the sheet. The checkbox is active by default.

The name of the sheet will be automatically generated. You can overwrite it in the text field if the Semi-finished product checkbox has not been activated.

Apply or discard value inputs

After completion of your data input you can create the new sheet. If you click Apply, the sheet will be inserted, and the dialogue window will remain open, allowing you to change the data and apply them to a different sketch if desired. Clicking OK inserts the sheets and closes the dialogue window. Clicking Cancel discards your value inputs and changes, without inserting the sheet.

Please note:

Incorrect inputs are marked with the symbol. If you move the cursor over the symbol, an error message will be displayed.

If the function cannot be executed with the entered data, the will appear next to the OK button. Move the cursor over the symbol to display an error message.

Example:

(1) Sketch
(2) Bend radius changed
(3) Sheet thickness
(4) Fitting direction

Only tangentially connected arcs are allowed for the Sheet along sketch function, since otherwise, no sheets and bend zones could be created.

 Related Topics

Create Base Sheet (3-D Sheet)