Externally Reference Parts (3-D)

Direct referencing

Most 3-D parts can be referenced during generation. This applies, for example, to generating extruded solids, revolved solids and solid primitives as well as the c-edge sweep. The corresponding input window then contains the Referenced checkbox.

If the Referenced checkbox is active, the dialogue for saving starts once the corresponding part has been generated.

Subsequent referencing

Drawing > Reference > Reference part, Save, Detail drawing

The Save part function also enables you to reference parts subsequently. You proceed as follows:

Activate the part to be referenced and choose the Reference part, Save, Detail drawing function.
The dialogue window for part referencing is displayed. Activate the External referencing option.
Activate the Also reference identical parts checkbox if you also want parts that are identical with the active part to be referenced. HiCAD then searches for parts that match the part to be referenced in terms of name and geometry. All found parts to which this applies are automatically referenced.
In the Part or Detail drawing section, activate the required radio button to define whether you want the part to be saved as a part (KRA file) or as a detail drawing.
In the Storage location, DB links section, define how you want the database entry to be made. The options are only available if you are using the HELiOS PDM system. You can then save the part with or without database entry.

In the DB document master for part section, you can display or re-generate the document master.
After selecting all required options, click Continue.
The subsequent dialogue and the required entries depend on the options you have chosen. The save location is evaluated first, followed by the option selected under Part or Detail Drawing.

Storage location
	Database, without part master	The part is entered in the database. Enter the master document data.
	Database, with New Master Part	The part is entered in the database with the new part master. For this to happen, first specify the part master data and then the document master data.
	Database, assign part master	The part is entered in the database, with an existing part master being assigned to it. Next, enter the document master data.
	Database, take over part master	The part is entered in the database with its current part master. Next, enter the document master data.
	Without database	The part is not entered in the database.

Part or Detail drawing
	Save as part	The part is saved under the specified name with the file name extension .KRA, namely in the directory predefined for referenced parts.
	Save as detail drawing	In addition to the KRA file, a construction file (.SZA) containing the referenced part is also created. Enter the part name, followed by the name of the detail drawing.
	Save as detail drawing, with options	The part is saved as a detail drawing with the file name extension .SZA. In contrast to the preceding option field, however, you can specify additional settings here, e.g. the number and type of saved views, the desired coordinate system etc.

Please note:

Referenced parts are saved as KRA files in the directory predefined for referenced parts.
Referenced parts are marked accordingly in the ICN.
Its part coordinate system is always saved together with the referenced part.
If a referenced part already exists under the selected name, the referencing is rejected.
It can sometimes be useful to create a superordinate dummy part (assembly) for referencing. This particularly applies if you want to replace the geometry of the actual part frequently.

It can often be useful to store a part that is frequently reused and should therefore be referenced in a separate assembly. To do this, create a new assembly and store the part in this assembly – either by means of a new construction or moving within the component structure. Then reference the assembly. This procedure makes sense, for example, in steel engineering to ensure the bidirectional associativity between construction and workshop drawing.

Alternatively, you can access the Reference part, Save, Detail drawing function via the context menu for parts: Right-click the part or the part name in the ICN.